Revolve (Solid) : Options and Results

Access: Open this function from one of the following locations:

Select Solid > Creation > Revolve from the menu bar.
Select Revolve on the popup menu if a sketch or 2D composite curve is selected.

Revolve a contour to add or remove material.

Create a new solid object, add to an existing solid object or remove material from a solid object by revolving a 2D sketch about an axis.

The following main options are available:

	New	Create a new solid object by revolving the selected entities about an axis. New revolves are considered independent objects.
	Add	Add to an existing solid object by revolving the selected entities about an axis. Added revolves are added to the active object.
	Remove	Remove material from a solid object by revolving the selected entities about an axis. Material is removed only from the active object.

Important: Objects created by New will be considered independent objects. Those created by Add will be added to the active object. For Remove operations, material will be removed only from the current active object.

Notes:

If only one object exists in the file it is automatically active, unless manually deactivated or if the active object is deleted. See Activate / Deactivate and Activating Objects.
For Add and Remove operations you can use wires or faces from a non-activated component (external reference).

Required Step 1

Select a closed 2D composite curve or sketch.

Notes:

If you enter Revolve immediately after creating a closed 2D composite curve or sketch, the entity is automatically included in Step 1.
If you select a sketch that contains more than one closed curve sequence, all closed curve sequences will be extruded. In order for a sketch to be selected, however, it must contain only closed curve sequences.

Required Step 2

Select the axis of revolution. The axis can be defined by picking an edge, line, datum axis, UCS axis (pick a UCS axis), 2 points, or the axis through the center of a cylindrical face, arc or circle.

Required Step 3

Set the revolution parameters.

The following parameters are displayed, depending on the selected main option:

New Revolve:	Add Revolve:	Remove Revolve:

Parameters:

New

This is a dropdown list of the following main options:

New	Create a new solid object by revolving the selected entities about an axis. New revolves are considered independent objects.
Add	Add to an existing solid object by revolving the selected entities about an axis. Added revolves are added to the active object.
Remove	Remove material from a solid object by revolving the selected entities about an axis. Material is removed only from the active object.

The default displayed option is determined as follows:

New, if there is no object.

Add, if there is an object and the last used option was New or Add.

Remove, if there is an object and the last used option was Remove.

Angle

This is a dropdown list of the following extrude options:

Angle	Revolve the selected geometry on one or both sides, by a given angle. For additional information, see: Add/New - Angle Remove - Delta/Reference
Angle Mid Plane	Revolve the selected geometry by the same amount equally in both directions. For additional information, see: Add/New - Angle Mid Plane Remove - Delta Mid Plane
To Reference	Revolve the selected geometry to a reference face or plane. For additional information, see: Add/New - To Reference Remove - Delta Mid Plane
To Closest	Revolve the selected geometry to the closest faces of an active object, according to a defined direction. This option is displayed for the Add and Remove main options only. For additional information, see: Add - To Closest Remove - To Closest

One Side

This is a toggle option One Side / Both Sides enabling you to revolve to one of both sides of the entity selected in the first step. This option is displayed for the Angle (if less than 360 degrees) and To Closest options.

One Side

Revolve on one side of the contour.
Example:Example:

Both Sides

Revolve on both sides of the contour.
Example:Example:

Invert Active Object

Use the Invert Active Object option as required. This parameter appears in the Add and Remove main options and is available only for open objects and deals with issues of object direction.

Thin Wall - Off

This toggle option enables you to create a thin-walled solid.
ExampleExample

Sketch	Extrude: Thin Wall Off	Extrude: Thin Wall On

The Thin Wall toggle option appears in the following functions:

Drive

Extrude

Revolve

For additional information, see Thin Wall.

Optional Step 1

Change the active object. This option is only available in the following cases:

for Add and Remove operations when creating a feature. The option is not available when editing a created feature.
if there is more than 1 object in the active part.

A toggle parameter is displayed; Keep Original Active Object / Activate Selected Object.

Keep Original Active Object	Keep the active object originally used in the function. This is the default option.
Activate Selected Object	Change the active object to the selected object. Pick an object as required.

Press <exit><exit>(middle mouse button) when finished. Click OK or Apply in the Feature Guide to complete the function.

When completed, the Revolve feature will appear in the Feature Tree as follows:

Revolve > New:	Revolve > Add:	Revolve > Remove:

Some functionality may be dependent on the product package. Contact your Reseller if you require a license.